Programming a cycle4.5 RotateHMI sl Turning184 Operating Manual, 01/2008, 6FC5398-7AP10-0BA0Parameter Description UnitT1 or T2 T1:• Groove depth at reference point ∅ (abs) or• Groove depth at reference point (inc)T2:• Groove depth in relation to reference point ∅ (abs) or• Groove depth in relation to reference point (inc)mmα0 Angle of the incline – (not for groove 1 and 2)The angle can be between -180 and +180°Longitudinal groove: α0 = 0° ⇒ Parallel to the Z axisTransverse groove: α0 = 0° ⇒ Parallel to the X axisA positive angle indicates rotation from the X axis to the Z axisDegreesα1, α2 Flank angle 1 or flank angle 2 - (not for groove 1)Asymmetric grooves can be described by separate angles. The angles can bebetween 0 and < 90°.DegreesFS1...FS4 or R1...R4 Chamfer width (1...4) or rounding radius - (not for groove 1) mmD • Maximum depth infeed for insertion – (not for finishing)• With zero: Insertion in one step – (not for finishing)D = 0: 1. cut is made directly to final depth T1D > 0: 1st and 2nd cuts are made alternately to infeed depth D, in order to achievea better chip flow and prevent the tool from breaking.All subsequent cuts are made directly to final depth T1.The lateral infeed for the alternate cuts is determined automatically in the cycle.Alternate cutting is not possible if the tool can only reach the groove base at oneposition.mmUX or U Finishing allowance in X or finishing allowance in X and Z – (not for finishing) mmUZ Finishing allowance in Z – (for UX and not for finishing) mmN Number of grooves (N = 1....65535)DP Distance between grooves (inc)DP is not displayed when N = 1mm1) Parameter description refers to plane G18; plane selection G17 or G19 possible in selection field(MD 52006: $MCS_DISP_PLANE_TURN)!
